Vision RV1126

A 39.5 mm, 8-layer onboard computer for FPV aircraft built around the Rockchip RV1126: two camera inputs, hardware video encoding, analog video out, IMU and barometer. Full KiCad sources, fabrication files and a 3D model.

Rendered view of the assembled Vision RV1126 board
Unbuilt and untested. No board has been manufactured from these files. The layout passes KiCad's design rule check with no clearance or short errors, but it has known weak points, listed under Known issues. Treat it as a design study and a starting point, not a proven product.

3D model

Drag to rotate, scroll to zoom. The processor, memory, eMMC, USB-C connector, microSD socket and one crystal use simplified block bodies of the correct outline; every other part uses its real package model.

Downloads: STEP for mechanical CAD, GLB for viewers, and a detailed GLB (large) that also includes copper, solder mask and silkscreen.

Specifications

ItemDetail
Size39.5 × 39.5 mm, four M3 mounting holes
Layers8 (top, ground, signal + 1.8 V, signal, power, signal, ground + NPU rail, bottom)
ProcessorRockchip RV1126, 409-ball 0.65 mm pitch
MemoryLPDDR3 1 GB, 178-ball
StorageeMMC 5.1 (153-ball) and microSD socket
Power5 V in over USB-C; RK809-2 power management IC plus one SY8089 buck regulator for the logic rail
CamerasTwo 22-pin 0.5 mm FFC connectors: one 4-lane MIPI CSI, one 2-lane MIPI CSI
Video outAnalog CVBS through an ADV7391 encoder
SensorsICM-20602 IMU (SPI), BMP280 barometer (I²C)
I/O on test padsDebug UART, two more UARTs, four PWM, I²C, USB host, CVBS, 5 V and 3.3 V
Parts258 footprints, both sides populated; passives mostly 0201 and 0402
Design rules0.09 mm track and gap, 0.35 mm via with 0.15 mm drill, through vias only, 41 vias in BGA pads
ToolsKiCad 10

Renders

Top side render
Top side
Bottom side render
Bottom side
Top copper layer routing
Top copper routing
Power plane layer
Power layer: one region per supply rail

Downloads

How to use it

1. Open and inspect the design

  1. Install KiCad 10.
  2. Unzip the KiCad project and open vision-rv1126.kicad_pro. The custom symbols and footprints load from the bundled lib folder.
  3. Open the board and run Inspect → Design Rules Checker. Expect no clearance or short errors, one unconnected ground ball and ten warnings; see Known issues.
  4. After any edit, press B to refill the zones before re-running the check. The plane layers depend on the project's 0.2 mm hole clearance rule being loaded.

2. Order bare boards

The fabrication pack was prepared with JLCPCB's published limits in mind, but it has not been through any manufacturer's own check. Upload the Gerber ZIP to their design review first and expect questions.

SettingValue
Layers8
Size39.5 × 39.5 mm
Minimum track / gap0.09 mm / 0.09 mm
Minimum drill0.15 mm, via pad 0.35 mm
Via processFilled and capped (the design has vias in BGA pads)
Surface finishENIG, for the 0.5 mm and 0.65 mm pitch BGAs
Impedance controlNot specified in the design; tracks are one uniform width

3. Assemble

4. First power-up

None of this has been done on real hardware; it is the sequence the design intends.

  1. Check for shorts between 5 V, 3.3 V, 1.8 V, the core rails and ground before applying power.
  2. Power from a current-limited 5 V supply through the USB-C connector and measure the rails at their decoupling capacitors.
  3. Connect a 3.3 V serial adapter to the debug UART pads (TP8 transmit, TP9 receive, any ground pad).
  4. Hold BOOT while applying power to enter Rockchip's USB download mode, then load firmware over the same USB-C port with Rockchip's tools.
  5. Start with a low memory clock. The DDR tracks are not length-matched, so the memory may not train at full speed.

5. Rebuild from the scripts

The board was generated by Python scripts that drive KiCad's scripting interface. They are included for reference; paths inside them point at the original working folder and need adjusting.

hand.sh        apply routes → build zones → refill → run DRC
plan.py        hand-planned DDR routing
maze.py        rule-checked path finder for all other nets
route.py       power and ground plane regions
lengths.py     DDR length report

Connectors and test pads

ReferenceFunctionNotes
J1USB-C5 V input and USB OTG data
J2microSDBottom side
J3Camera 0, 4-lane MIPI CSI22-pin 0.5 mm FFC, Raspberry Pi 22-pin pin order, 3.3 V on pin 22
J4Camera 1, 2-lane MIPI CSI22-pin 0.5 mm FFC, bottom side
SW1 / SW2Reset / Boot
D2 / D3Green / red LEDActivity and status

Test pads

PadSignalPadSignal
TP15 V systemTP15 / TP16UART0 TX / RX
TP3Power-on keyTP17CVBS video out
TP4 – TP7PWM0 – PWM3TP19 / TP20USB host D+ / D−
TP8 / TP9Debug UART TX / RXTP215 V
TP10 / TP11UART3 TX / RXTP23 / TP24I²C3 SCL / SDA
TP2, 12 – 14, 18, 22GroundTP253.3 V

Design notes

Known issues

IssueDetail
DDR lengths are not matchedSpread of 4 to 8 mm within each data byte and 16 mm across address and control lines; strobe pairs differ by up to 2.5 mm. The memory may only work at reduced speed.
Never checked by a manufacturer0.09 mm tracks, 0.15 mm drills, vias in BGA pads and plane webs of about 0.1 mm between vias are all at the edge of standard capability.
Supply currents not verifiedThe 5 V, buck output and 3.3 V system nets still have 0.09 mm sections near the power management IC, backed by patchy copper pours. No current or voltage-drop calculation was done.
1.8 V distributionShares an inner layer with signals and is stitched together from many pieces by tracks.
One unconnected ground ballProcessor ball AA10, one of about a hundred ground balls.
Tight assembly spacingThe eMMC courtyard overlaps the microSD socket's and one camera connector's; four mounting-hole pads fall inside a courtyard.
No controlled impedanceUSB, MIPI and DDR pairs are not routed as coupled, impedance-controlled pairs.
Decoupling placementSeveral decoupling capacitors sit far from the chips they serve.